PCB Layout Action Checklist
Project
IMU-Bridge-2026
Purpose
This checklist captures the agreed PCB layout constraints, placement targets, routing priorities, and pre-routing verification items discussed for the IMU-Bridge-2026 board.
Board setup
- Board outline: rectangle
- Size: 25.80 mm x 20.80 mm
- Keep board work constrained to this outline before routing
Mounting holes
- MH1-MH4 are 2.2 mm non-plated mounting holes
- Verify final keep-out setting before routing
- Keep-out was discussed in both 0.5 mm and 0.3 mm radial-from-edge forms during review; confirm the intended final value before locking placement and routing
Placement order
- Place J1, U4, U1 first
- Place U2 and U3 second
- Place passive parts last
Target placements
- J1: top edge, centered at X = 12.90 mm, Y = 19.30 mm, rotation 180 degrees
- U4: top-left region at X = 3.50 mm, Y = 15.00 mm
- U1: board center at X = 12.90 mm, Y = 10.40 mm
- U2: lower-left region at X = 7.00 mm, Y = 4.50 mm
- U3: lower-right region at X = 18.80 mm, Y = 4.50 mm
Functional grouping intent
- Power section on the left
- MCU in the center
- IMUs on the right/lower area as specified by the placement brief
- Connector on the board edge
- Keep schematic and PCB readability high by avoiding unnecessary congestion and preserving clean fanout directions
Critical local-placement requirements
- C11 must be placed extremely close to U2 CPOUT/nCS
- C12 must be placed extremely close to U3 CPOUT/nCS
- C9 must be close to U2 REGOUT
- C10 must be close to U3 REGOUT
- C7 must be close to U2 power pins
- C8 must be close to U3 power pins
- C5 must be close to U1 VDD
- R7 and C6 must remain close to U1 NRST
- R5 should remain close to the BOOT0/SWCLK area
- SWD test points TP3 and TP4 should remain convenient for probing/programming
Pre-routing placement verification
Before routing, confirm all of the following:
- J1 is actually on the top edge and centered
- U4 is in the left-side power entry area
- U1 is near the board center
- U2 and U3 are correctly separated and positioned at the lower half as intended
- C11 and C12 are the closest possible passives to the IMU CPOUT pins
- C9 and C10 are near REGOUT pins
- C7 and C8 are near IMU supply pins
- TP1-TP4 do not block primary routing channels
- Mounting hole keep-outs do not interfere with the connector, IMUs, or test points
- All placed parts fit fully inside the board outline
Layer usage strategy
- Top layer: primary routing layer
- Bottom layer: keep as continuous GND as much as possible
- Avoid treating Bottom as a general signal-routing layer
Routing allocation by net type
Top layer preferred or required
- +5V input path from J1 to U4
- VCC_3V3 distribution from U4 to U1, U2, and U3
- MAIN_SCL and MAIN_SDA
- SUB_SCL and SUB_SDA
- SWDIO and SWCLK
- NRST, BOOT0, AD0_U3
- REGOUT_U2 and REGOUT_U3 local connections
- CPOUT_U2 and CPOUT_U3 local connections
Bottom layer reserved mainly for
- GND pour
- Ground stitching support
- Only minimal auxiliary routing if absolutely necessary
Routing constraints
- Keep I2C entirely on Top
- Do not route I2C under U1, U2, or U3
- Keep CPOUT and REGOUT local loops extremely short
- Keep power paths direct and reasonably wide
- Preserve Bottom copper continuity for ground as much as possible
Routing order recommendation
- CPOUT_U2 and CPOUT_U3
- REGOUT_U2 and REGOUT_U3
- +5V and VCC_3V3
- SUB_SCL and SUB_SDA
- MAIN_SCL and MAIN_SDA
- SWDIO and SWCLK
- NRST, BOOT0, AD0_U3
- Ground pours and stitching review
Known issues from layout review
- Earlier layout inspection suggested key parts were not yet at target coordinates
- Component envelope was observed larger than the board outline during review, indicating layout was not yet ready for routing
- Airwire count and dense packing were flagged as reasons not to start routing until placement is refined
- Current layout should be re-checked before routing to ensure all components are inside the board and critical capacitors are close enough to their pins
Ready-to-route gate
Do not begin routing until these are all true:
- All critical components are inside the board outline
- Placement matches the target zones
- IMU support capacitors are placed tightly
- Test points do not obstruct escape routing
- Mounting-hole keep-outs are finalized
- Stackup/layer intent matches the intended 2-layer top-plus-bottom routing approach if that is the final manufacturing target
- Remaining airwires are consistent with an unrouted but placeable board rather than a placement problem
PCB 布局执行清单(中文版)
项目
IMU-Bridge-2026
文档用途
本文档用于汇总本次讨论中已经明确的 PCB 布局约束、目标摆位、关键器件相对位置关系、Top/Bottom 分层布线原则,以及开始正式布线前必须完成的检查项。中文版补充在英文版之后,便于后续直接作为执行清单使用。
1. 板框与基本约束
- 板框为矩形。
- 尺寸为 25.80 mm × 20.80 mm。
- 在正式布线前,所有元件都应当完整落在该板框范围内。
- 任何器件如果仍有包络超出板框、与安装孔禁布冲突、或压缩掉关键走线通道,都不应进入布线阶段。
2. 安装孔要求
- MH1-MH4 为 2.2 mm 非电镀安装孔(NPTH)。
- 在讨论过程中,安装孔 keep-out 曾在 0.5 mm 与 0.3 mm 两种半径扩展方案之间反复比较。
- 因此在最终锁定布局与开始布线之前,必须再次确认:
- 最终采用的是 0.3 mm from hole edge
- 还是 0.5 mm from hole edge
- 这一项会直接影响边缘器件、测试点与局部走线可行性。
3. 摆件顺序
按已讨论的执行顺序,布局应遵循以下步骤:
- 先放 J1、U4、U1
- 再放 U2、U3
- 最后放所有无源器件
这样做的目的是先确定接口、电源入口和主控中心,再围绕关键芯片把去耦、电源支撑、调试与总线相关的小器件逐步压紧。
4. 主器件目标坐标
- J1:上边缘居中,X = 12.90 mm, Y = 19.30 mm,旋转 180°
- U4:左上角电源区域,X = 3.50 mm, Y = 15.00 mm
- U1:板中心,X = 12.90 mm, Y = 10.40 mm
- U2:左下区域,X = 7.00 mm, Y = 4.50 mm
- U3:右下区域,X = 18.80 mm, Y = 4.50 mm
这些坐标是本次 brief 中最核心的布局基准。如果这些主器件没有落到位,后续布线讨论就没有意义,因为电源、I2C、调试接口和测试点关系都会随之失真。
5. 功能分组意图
布局时应保持以下功能分区:
- 左侧:电源区
- 中间:MCU 主控区
- 下方左右:双 IMU 区
- 板边:连接器与便于接触的测试点/接口区
即使不能完全机械对称,也要保证功能流向清晰:
- 电源从连接器进入后尽快到稳压器
- 稳压后的 3.3V 再分配给 MCU 和两颗 IMU
- I2C 总线从 MCU 向上连接器、向下双 IMU 发散
6. 关键局部摆位要求
以下器件关系优先级最高,必须在布线前先满足:
- C11 必须尽量贴近 U2 的 CPOUT/nCS 引脚
- C12 必须尽量贴近 U3 的 CPOUT/nCS 引脚
- C9 必须贴近 U2 的 REGOUT
- C10 必须贴近 U3 的 REGOUT
- C7 必须贴近 U2 的电源脚
- C8 必须贴近 U3 的电源脚
- C5 必须贴近 U1 的 VDD
- R7 与 C6 必须贴近 U1 的 NRST
- R5 应靠近 BOOT0/SWCLK 区
- TP3、TP4 要方便 SWD 调试探测和下载
其中,C11/C12 的贴脚要求是优先级最高的局部摆位规则。如果这两颗电容离各自 IMU 的对应引脚过远,那么即使其他器件位置都“看起来差不多”,布局仍不应视为可布线状态。
7. 布线前位置核对清单
在开始任何自动布线或人工布线前,至少应逐项确认:
- J1 是否真的位于上边缘并居中
- U4 是否处于左侧电源入口区
- U1 是否接近板中心
- U2/U3 是否位于下半区且左右关系合理
- C11/C12 是否是距离 IMU CPOUT 最近的无源器件
- C9/C10 是否已经靠近 REGOUT
- C7/C8 是否已经靠近 IMU 供电脚
- TP1-TP4 是否不会堵住主走线通道
- 安装孔禁布是否已经不会干扰连接器、IMU 和测试点
- 所有器件是否已经完全落入板框范围
任何一项如果未满足,都应先修正布局再考虑走线。
8. 分层使用策略
目前讨论形成的原则是:
- Top layer:主布线层
- Bottom layer:尽可能保持连续地铜
- 不要把 Bottom 当作普通信号层随意使用
换句话说,这块板的理想状态是:
- 主信号几乎都在 Top 层完成
- Bottom 层尽量用于 GND plane / GND pour
- 若必须借 Bottom 过线,也只能是少量、短距离、非关键的补充连接
9. 按网络类型分配布线层
应优先或必须走 Top 的网络
+5V:从 J1 到 U4 的输入路径
VCC_3V3:从 U4 输出到 U1/U2/U3 的主电源分配
MAIN_SCL / MAIN_SDA
SUB_SCL / SUB_SDA
SWDIO / SWCLK
NRST
BOOT0
AD0_U3
REGOUT_U2 / REGOUT_U3 本地连接
CPOUT_U2 / CPOUT_U3 本地连接
Bottom 层主要保留给
- GND 铺铜
- 地过孔缝合
- 仅在绝对必要时才允许的少量辅助走线
10. 关键布线约束
- I2C 必须保持在 Top only
- 不要从 U1、U2、U3 下方穿 I2C
- CPOUT 与 REGOUT 本地小回路必须极短
- 电源路径应尽量直接且线宽适当
- Bottom 地铜连续性要尽量保留,避免被过多信号切碎
11. 推荐布线顺序
建议按以下顺序开始走线:
CPOUT_U2、CPOUT_U3
REGOUT_U2、REGOUT_U3
+5V、VCC_3V3
SUB_SCL、SUB_SDA
MAIN_SCL、MAIN_SDA
SWDIO、SWCLK
NRST、BOOT0、AD0_U3
- 最后再统一检查地铜与缝合过孔
这样的顺序是为了先锁定最短、最敏感、最不允许绕路的局部网络,再处理一般总线与调试线。
12. 之前布局审查中发现的问题
在前面的讨论中,布局检查暴露出若干尚未满足“可布线”条件的问题:
- 有检查结果显示关键器件尚未到目标坐标区
- 元件总体包络曾大于板框,说明布局还没有完全收进板内
- Airwire 数量和密度偏高,表明此时不应直接进入布线
- 一些关键电容(尤其 C11/C12)没有明显贴到各自引脚旁边
这些问题意味着:在未完成位置细化之前,即使“能勉强连上”,也不应视为工程上合格的布局状态。
13. 开始布线前的最终门槛
只有在以下条件全部满足时,才建议开始布线:
- 关键器件全部位于板框内
- 主器件位置已接近或达到目标区域
- IMU 周边关键支撑电容已紧贴放置
- 测试点不会妨碍主走线通道
- 安装孔禁布已经最终确认
- 层叠与实际生产目标一致
- 剩余 airwire 只是“尚未走线”而不是“布局错误”的结果
14. 中文版补充结论
这份 PCB 执行清单的核心目标,不是追求“先把线连上”,而是确保在开始布线之前,器件摆位已经满足以下三类约束:
- 机械约束:板框、安装孔、边界和测试点可落地
- 电气约束:CPOUT、REGOUT、去耦、电源和 I2C 的关键局部关系正确
- 可制造与可调试约束:连接器、测试点、地铜和层使用策略合理
只要这三类约束中还有明显未满足项,就应继续做布局细化,而不是急于自动布线。